In the drawing is not possible to remove ghost so easy as previous example - but I have found quick solution for a drawing too:
1. Create new EMPTY drawing (set name as "removed_ghost.drw" - for example)
2. Merge new drawing with original *.drw file (problematic drawing): Layout > Import Drawing/Data
3. Delete First Sheet
4. Save drawing
5. Delete original *drw file from the Workspace
6. Rename removed_ghost.drw to original file name System will inform to you that same name exists - it is OK. Your "new drawing" is without Ghosts Objects - Update this objects as "reuse" windchill function
7. Check In modified drawing into WCH (wihout Ghost Objects)
Note: remove ghosts from a drawings is possible to run with custom Mapkey too
I hope that my solutions will help you to remove Ghost Objects from the assemblies and drawings.
Tips and TricksPosted by Ing. Vladimir Palffy Thu, June 22, 2017 10:14AM PTC creo Parametric extracts values for parameters from model data and displays them in tables when the parameters are included within a repeat region. These parameters can be user-defined or they can already be defined by Pro/REPORT.
Displays the name of an assembly member.
Lists the names of all user-defined parameters in an assembly member.
Lists the values of all user-defined parameters in an assembly member.
Displays the type (part or assembly) of an assembly member.
User-defined parameter in an assembly member. For example: &asm.mbr.drw_number (where drw_number is Creo model parameter)
Displays the name of a family table instance.
Displays the name of a family instance parameter name.
Displays the ID of a family table parameter if it is a dimension.
Displays the name of a family table parameter.
Displays the value of a family table parameter for an instance.
Lists the names of all user-defined parameters in a layout.
Lists the values of all user-defined parameters in a layout.
Lists the names of all user-defined parameters in a model.
Lists the values of all user-defined parameters in a model.
Displays the number assigned to each record in a repeat region.
· Duplicates – Allows multiple rows with the same data to exist. This is why we see several rows that look identical to each other. Unfortunately, Duplicates will not show a quantity in the quantity column (which is why we don’t see any right now).
· No Duplicates – Does not allow duplicate rows to exist in the table. For any two or more rows that are the same, the repeat region will calculate the total number of these rows and report that quantity in the second column.
· No Dup/Level – Does not allow duplicate rows to exist for each level of the assembly. This option only works if you have your level reporting set to Recursive.
· Recursive – Shows all levels of the assembly, including the assembly itself. Sub-assemblies will show all of their components on the table as well.
· Flat – Only reports the items at the top level of the current assembly.
The next option, Min Repeats, allows you to specify the minimum number of repetitious rows allowed in the repeat region. The default is 1, which will allow for blank lines to appear if data is missing from certain components. I recommend keeping this setting at 1 unless you have an advanced table function you are trying to work with that requires the number to be set to something else.
· Bln By Part - When you suppress or replace a component to which a BOM balloon is attached, this command reattaches the balloon to another placement of the same part. If no other copy of the part exists in the assembly, then the BOM balloon disappears from the drawing.
· Bln By Comp – Specifies that simple BOM balloons reattach themselves to whatever component replaced the one that originally owned the BOM balloon.